Export Parameters as iProperties

October 16, 2018 Randall Mabery

I recently made a mistake.  While working on a project, I should have marked some User Parameters to Export as iProperty.  Unfortunately, I didn't realize this until I was about 300 parts in.  I sure didn't want to open up each part and manually check those boxes.

For those unsure of what I'm referring to, in Inventor you can export Parameters as iProperties.  This is a very easy and simple way of getting model data onto your Bill Of Materials or Parts Lists.  You accomplish this by checking the box in the Export Parameter column of the Parameters dialog box.


Parameters

Once you've marked one or more parameters to Export, you can right mouse click on one of the marked Parameters and choose Custom Property Format from the Contextual Menu.

  Custom Property FormatFrom there, you can format the iProperty to suit your needs.

As I mentioned, I sure wasn't going to open each part and export the necessary Parameters and set their format.  Automation to the rescue!

The Inventor Parameter API object has a Property called ExposedAsProperty.  This is set to a Boolean that controls whether or not the parameter is exposed as an iProperty.  Assuming I've already declared and set the oUserParam object:

oUserParam.ExposedAsProperty = True

Once that property has been set to True, you can set all the options for the formatting thru the Property called CustomPropertyFormat.  

oUserParam.CustomPropertyFormat.PropertyType = kTextPropertyType
oUserParam.CustomPropertyFormat.Precision = kThreeDecimalPlacesPrecision
oUserParam.CustomPropertyFormat.ShowLeadingZeros = False
oUserParam.CustomPropertyFormat.ShowTrailingZeros = True
oUserParam.CustomPropertyFormat.ShowUnitsString = True
oUserParam.CustomPropertyFormat.Units = "in"

The PropertyType Property determines if the iProperty will be a Number or a Text Property.  It uses the CustomPropertyTypeEnum.

The Precision Property determines the precision of the iProperty.  It uses the CustomPropertyPrecisionEnum.

The ShowLeadingZeros and ShowTrailing Zeros determine if leading or trailing zeros are included in the iProperty.  These are set to Booleans.

The ShowUnitsString Property determines if the unit string is shown in the iProperty.

The Units Property determines the units to use in the iProperty.

You can look up the enumerators in the Inventor Programming/API Help for more information on them. 

In my case, I had three specific Parameters (Height, Length, Width) in each part that I wanted to expose.  Admittedly, there are many ways I could have done this.  I chose to loop thru all the User Parameters and if the Parameter name matched what I wanted, I exported it and set its format to the way I needed it.

Below is the final code:

Imports Inventor.CustomPropertyPrecisionEnum
Imports Inventor.CustomPropertyTypeEnum

' Declarations
Dim oPart As PartDocument
oPart = ThisApplication.ActiveDocument

Dim oCompDef As PartComponentDefinition
oCompDef = oPart.ComponentDefinition

Dim oUserParams As UserParameters
oUserParams = oCompDef.Parameters.UserParameters

' Loop thru parameters and set specific parameters to export as iProperty
For i = 1 to oUserParams.Count
    sName = oUserParams.Item(i).Name
    Select Case sName
        Case "Height", "Length", "Width"
            oUserParams.Item(i).ExposedAsProperty = True
            oUserParams.Item(i).CustomPropertyFormat.PropertyType = kTextPropertyType
            oUserParams.Item(i).CustomPropertyFormat.Precision = kThreeDecimalPlacesPrecision
            oUserParams.Item(i).CustomPropertyFormat.ShowLeadingZeros = False
            oUserParams.Item(i).CustomPropertyFormat.ShowTrailingZeros = True
            oUserParams.Item(i).CustomPropertyFormat.ShowUnitsString = True
            oUserParams.Item(i).CustomPropertyFormat.Units = "in"
    End Select
Next I

I ran this code as an external rule.  I used a custom application that I wrote that allows me to run rules against a large group of parts.  I accomplished in a few minutes what would have taken me hours to do....and I know it's all correct!

If you have any questions, be sure to post in the comments below.

Happy Coding!

Randy

About the Author

Randall Mabery

I love the technology, thoroughly enjoy helping people find solutions and believe in the software. I train individuals in the use of Autodesk design software such as Inventor and AutoCAD. The most satisfying part of my job is working on automation solutions for clients, assisting them in streamlining their design process and automating tasks.

Follow on Linkedin More Content by Randall Mabery
Previous Article
Getting additional post processors for Inventor HSM and Fusion360 CAM
Getting additional post processors for Inventor HSM and Fusion360 CAM

Autodesk Inventor HSM and Fusion 360 come loaded with a lot of options for the post processors, but the pos...

Next Article
Adding Features to Custom Content Center Parts
Adding Features to Custom Content Center Parts

Creating Custom Content Center Parts (CCCP) has many benefits but modifying a previously published library ...

×

Get Tips Delivered.

Subscribe to Email Updates.

First Name
Last Name
Country
Thank you!
Error - something went wrong!